my-first-fusion-plugin-script-py/BasicScript.py at main · ADN-DevTech/my-first-fusion-plugin-script-py · GitHub

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"""Create a simple box"""
from dataclasses import dataclass

import traceback
import adsk.core
import adsk.fusion
epsilon = 1e-6
# import adsk.cam

# Initialize the global variables for the Application and UserInterface objects.
app = adsk.core.Application.get()
ui  = app.userInterface

@dataclass
class BoxParameters:
    border_thickness : float
    bottom_thickness : float
    inner_width : float
    inner_length : float
    inner_height : float
    fillet_size : float

    def __init__(self, border_thickness: float, bottom_thickness:float, inner_width:float, inner_length:float, inner_height:float, fillet_size:float):
        self.border_thickness = border_thickness
        self.bottom_thickness = bottom_thickness
        self.inner_width = inner_width
        self.inner_length = inner_length
        self.inner_height = inner_height
        self.fillet_size = fillet_size


def create_box(design: adsk.fusion.Design, parameter: BoxParameters, margin: float, body_name:str, component_name:str)->adsk.fusion.Component:
    input_units = 'mm'
    border_thickness = parameter.border_thickness
    bottom_thickness = parameter.bottom_thickness
    inner_width = parameter.inner_width
    inner_length = parameter.inner_length
    inner_height = parameter.inner_height
    fillet_size = parameter.fillet_size
    # We may take different input units than default units in Fusion. We'll need to convert them first.
    units_manager = design.fusionUnitsManager
    default_units = units_manager.internalUnits
    border_thickness = units_manager.convert(border_thickness, input_units, default_units)
    bottom_thickness = units_manager.convert(bottom_thickness, input_units, default_units)
    inner_width = units_manager.convert(inner_width, input_units, default_units)
    inner_length = units_manager.convert(inner_length, input_units, default_units)
    inner_height = units_manager.convert(inner_height, input_units, default_units)
    fillet_size = units_manager.convert(fillet_size, input_units, 'mm')
    margin = units_manager.convert(margin, input_units, default_units)

    # Get root component
    rootComponent = design.rootComponent

    # Get references to the sketches and plane
    sketches = rootComponent.sketches
    xzPlane = rootComponent.xZConstructionPlane

    # Create a new sketch and get lines reference
    sketch_outer_base = sketches.add(xzPlane)

    base_width_total = border_thickness * 2.0 + inner_width
    base_length_total = border_thickness * 2.0 + inner_length

    pointOne = adsk.core.Point3D.create(margin + -base_width_total / 2.0,-base_length_total / 2.0, 0)
    pointTwo = adsk.core.Point3D.create(margin + base_width_total / 2.0, base_length_total / 2.0, 0)

    # Create a rectangle sketch
    rectangles = sketch_outer_base.sketchCurves.sketchLines
    rectangles.addTwoPointRectangle(pointOne, pointTwo)

    # Create extrusion input
    base_sketch_profile = sketch_outer_base.profiles.item(0)
    extrudes = rootComponent.features.extrudeFeatures
    base_extrude_newbody = extrudes.createInput(base_sketch_profile, adsk.fusion.FeatureOperations.NewBodyFeatureOperation)

    # Define that the extent is a distance of bottom thickness + inner height.
    # Our input unit is mm, we'll need to convert it into cm.
    base_extrude_distance = adsk.core.ValueInput.createByReal((bottom_thickness + inner_height))
    base_object_extend_definition = adsk.fusion.DistanceExtentDefinition.create(base_extrude_distance)
    base_extrude_newbody.setOneSideExtent(base_object_extend_definition, adsk.fusion.ExtentDirections.PositiveExtentDirection)
    base_extrude_newbody.isSolid = True
    new_extrude_feature = extrudes.add(base_extrude_newbody)

    # Let's dig a hole in the new created box.
    # We need two points to find a face. We want to find top and bottom face as beginning and end here.
    base_top_point1 = adsk.core.Point3D.create(margin + -base_width_total / 2.0, bottom_thickness + inner_height, -base_length_total / 2.0)
    base_top_point2 = adsk.core.Point3D.create(margin + base_width_total / 2.0, bottom_thickness + inner_height, base_length_total / 2.0)

    base_bottom_point1 = adsk.core.Point3D.create(margin + -base_width_total / 2.0, 0.0, -base_length_total / 2.0)
    base_bottom_point2 = adsk.core.Point3D.create(margin + base_width_total / 2.0, 0.0, base_length_total / 2.0)

    # Let's get the new body
    base_extrude_item = new_extrude_feature
    base_extrude_body = base_extrude_item.bodies.item(0)

    # Find the faces.
    bottom_face = None
    sketch_inner_base = None
    for face in base_extrude_body.faces:
        top_point1_flag = face.isPointOnFace(base_top_point1, epsilon)
        top_point2_flag = face.isPointOnFace(base_top_point2, epsilon)
        bottom_point1_flag = face.isPointOnFace(base_bottom_point1, epsilon)
        bottom_point2_flag = face.isPointOnFace(base_bottom_point2, epsilon)
        if top_point1_flag and top_point2_flag:
            sketch_inner_base = sketches.add(face)
            pointOne = adsk.core.Point3D.create(-inner_length / 2.0,margin -inner_width / 2.0, 0)
            pointTwo = adsk.core.Point3D.create(inner_length / 2.0, margin + inner_width / 2.0, 0)
            rectangles = sketch_inner_base.sketchCurves.sketchLines
            rectangles.addTwoPointRectangle(pointOne, pointTwo)
        if bottom_point1_flag and bottom_point2_flag:
            bottom_face = face

    # Have we found top face and bottom face?
    if (bottom_face is not None) and (sketch_inner_base is not None):
        # There are two profiles
        # The first one is the border between the new sketch and first sketch
        # The second one is the sketch we've just drawn.
        # We'll need the second one here.
        base_inner_profile = sketch_inner_base.profiles.item(1)
        bottom_object_extend_definition = adsk.fusion.ToEntityExtentDefinition.create(bottom_face, False, adsk.core.ValueInput.createByReal(-bottom_thickness))
        base_extrude_cut = extrudes.createInput(base_inner_profile, adsk.fusion.FeatureOperations.CutFeatureOperation)
        base_extrude_cut.setOneSideExtent(bottom_object_extend_definition, adsk.fusion.ExtentDirections.NegativeExtentDirection)
        base_extrude_cut.isSolid = True
        extrudes.add(base_extrude_cut)

    # Let's add fillet feature
    fillet_features = rootComponent.features.filletFeatures
    fillet_input = fillet_features.createInput()

    fillet_edges = adsk.core.ObjectCollection.create()
    for edge in base_extrude_body.edges:
        fillet_edges.add(edge)

    fillet_size_value_input = adsk.core.ValueInput.createByString(f'{fillet_size} mm')
    fillet_input.edgeSetInputs.addConstantRadiusEdgeSet(fillet_edges, fillet_size_value_input, False)

    fillet_features.add(fillet_input)

    base_extrude_body.name = body_name
    new_body = base_extrude_body.createComponent()
    component = new_body.parentComponent
    component.name = component_name

    return component


def run(_context: str):
    # Units are in mm
    bottom_box_parameters = BoxParameters(4.0, 4.0, 190.0, 390.0, 110.0, 0.5)
    # The bottom, I need to add the border thickness to the inner width/length
    top_box_parameters = BoxParameters(4.0, 4.0, 198.0, 398.0, 30.0, 0.5)
    # I want to put it a base margin of 50mm between each box in the design view.
    base_margin = 50.0
    """This function is called by Fusion when the script is run."""
    default_units = None
    try:
        # Get the design through active product
        design = adsk.fusion.Design.cast(app.activeProduct)

        if not design:
            ui.messageBox("The DESIGN workspace must be active when running this command.")
            return
        create_box(design, bottom_box_parameters, (-bottom_box_parameters.inner_width - bottom_box_parameters.border_thickness) / 2.0 - base_margin, "bottom_body", "box")
        create_box(design, top_box_parameters, base_margin + (top_box_parameters.border_thickness + top_box_parameters.inner_width) / 2.0, "top_body", "lid")

        app.log(app.data.activeProject.rootFolder.name)


    except:  #pylint:disable=bare-except
        # Write the error message to the TEXT COMMANDS window.
        app.log(f'Failed:\n{traceback.format_exc()}')